ME-546 Computer Aided Manufacturing

Lesson 7 -- Shaft Tray Drawing

 

Pro/ENGINEER Functions

Drawing         Projection
General         Dimensions

 

Design Objectives

In this lesson, you will use 3D part to create a draft containing the shaft tray's three orthographic views and one isometric view. You will also learn how to attach dimensions to this drawing. When you complete this lesson, your drawing should resemble the one shown in Figure III.7-1.

 

Modeling Strategy

I. Use Drawing to create the draft.

II. Use the General view to attach the primary view to the draft.

III. Use the Projection view to attach the remaining orthographic views.

IV. Use the General view to attach the isometric view.

V. Use Dimensions to add any appropriate dimensions.

 

Detailed Construction

I. Use Drawing to create the draft.

1. MODE - Drawing - Create
2. Enter drawing name:
   At this point, the program provides you with a list of standard drawing sizes.
3. Select drawing size B.

II. Use the General view to attach the primary view to the draft.

1. Create the primary view:
1. - Views
2. - Model name : [tray]
3. Add View - General - Full View - No Xsec - No Scale - Done
   The first view in a drawing is always the general view, which is a basic view where the object is placed on the draft as an isometric, and the user then reorients it as one of the orthographic views. All projections must be made in reference to the general view.
4. Select the proximity of the top left-hand corner to place this view.
2. Reorient this view to display the top orthographic view of the tray. You may need to zoom in on the view to do this.
1. - Top
2. Use Query Sel to select the top face.
3. - Right
4. Use Query Sel to select the right face.
5. - Done/Return

III. Use the Projection option to attach the remaining orthographic views.

1. Create the Front view:
1. - Add View
   Notice that the projection option is automatically selected.
2. - Done
3. Select the proximity of the bottom left-hand corner of the drawing page.
   This defines the projection for the front view.
2. Create the Side view:
1. - Add View
2. - Done
3. Select the proximity of the top right corner of the drawing page.

IV. Use the General view to attach the isometric view.

1. - Add View - General - Done
2. Select the proximity of the bottom right corner to place this view.
3. - Done/Return - Done/Return

V. Use Dimensions to add appropriate dimensions.

1. One way to add dimensions to the drawing:
1. Drawing - Detail - Show - Dimension (this is a button) - Part&View - Show All - Close
2. Zoom the top view:
   Indicate two points to define the Zoom area.
3. Use Erase, Create, Move, etc. to adjust the dimensions.
4. Make the dimensions look as good as the figure.

Creat a B-size drawing file with your own COMPLETE, custom frame format and submit the file with your assignment.